How to get simple movement instead of macro

This option came useful when the controller doesn't support some common macro , or you prefer don't use it.

Is possible expand the canned cycles in simple movements ,  just cleari the macro template text from post processor dialog.

Note: Tapping cycle not supported yet.

Thread cycle example :

By default is used the G92 macro, here the template :

G92{FIRST_DIA_CODE}{END_Z_CODE}{PITCH_CODE}
{PLACEHOLDER_DIAMETERS_LIST}

and the output g-code will be like this :

G92 X9.535 Z-15. F1.5 X9.15 X8.798 X8.528 X8.301 X8.1

Now clear the thread cycle template from post processor in this way :

The output will become like this :

X9.535
G32 Z-15. F1.5
G0 X12.
Z1.5
X9.15
G32 Z-15. F1.5
G0 X12.
Z1.5
X8.798
G32 Z-15. F1.5
G0 X12.
Z1.5
X8.528
G32 Z-15. F1.5
G0 X12.
Z1.5
X8.301
G32 Z-15. F1.5
G0 X12.
Z1.5
X8.1
G32 Z-15. F1.5
G0 X12.

Deep hole drilling example :

Default Template :

<code>G83{ABSOLUTE_Z_DEPTH}{POINT_R_CODE}{STEP_CODE}{FEED_CODE} G80

Default Output :

<code>G83 Z-30. R0.Q10. F0.12 G80

Now deleted the template , for lathe in this case :

And this will be become the output :

X0.
<code>X0.
G1 Z-10. F0.12
G0 Z2.
Z-9.
G1 Z-20. F0.12
G0 Z2.
Z-19.
G1 Z-30. F0.12
G0 Z2.

Still need help? Contact Us Contact Us